SS Button Part Drawing

In the NES controller guided project that we spent a lot of time on

lately,

there's been a lot of talk about a good CAD process,

and that good CAD process involves

four steps that we talked about a lot,

but it also includes a fifth step,

and that fifth step is really important.

It's

a step

we think of as

presenting

the model

to other people. We do that in the form of renders, in

the form of engineering drawings, in the form of animations, in the form of

all kinds of things.

And in this particular video, I'm gonna introduce you

to the notion of creating an engineering drawing

as a way of presenting

information in a model to somebody else.

OK.

So,

how are we gonna do this?

Well,

we're gonna do this for the start select button

for the NES controller,

which you can see now in Onshape pulled up in it's part studio.

I am

just

to keep us organized here,

I'm working in my NES document.

Then within my NES document,

I now have four

important folders,

a new one from the last time we had a video.

The new

folder that has been created is

the drawings folder. Inside that drawings folder, there isn't anything

yet because we haven't created any drawings, but we're gonna do that right now.

and as a reference

and a way for you to get started with the process of creating a drawing, I am going

to

upload a model drawing

that we're going to attempt to

copy.

OK.

Now, there is some value in copying.

It gives us a chance to

work through the issues without having to be

too creative about what should be there,

but that's why it's a guided

exercise.

It's the kind of thing where

if

you know how to make an engineering drawing,

you're in good shape.

You can just go ahead and make an engineering drawing,

but if you want some guidance,

I'm showing you now in this video

how to do that.

So, what we're going to try to do

is we're going to try to create this drawing here,

and to make it even more exciting,

we are going to take this one-sheet drawing and we're going to try to

produce,

at least I'll show you how to make a two-sheet drawing so you

can get a second sheet in there if that's what you needed to do.

So, we're gonna start by

understanding the job that needs to be done, and the job

that needs to be done is to create this engineering drawing

with the same information.

It doesn't need to be exact in the placement of everything,

but we're gonna try to create this engineering drawing.

So, it's a good idea for me to study it for just a moment.

OK.

We

have over here our orthographic projections.

This is our front view.

This is our right view;

this is our top view.

There's also a bottom view that's shown here,

and then we have our

traditional isometric view here,

but then we have an underside

of the isometric view.

And then, we have some auxiliary views,

and one of the auxiliary views that we have is this section AA,

which is defined by this slice right here,

this

AA section marker.

And then, we also have

this detail

view,

detail B, which is shown right here.

We also have some notes.

We have

a lot of information in the title block,

and

we're gonna now learn how to create

a drawing like this.

So, this is here, and I put it in this

folder just for reference. We're gonna go back and forth

on it.

But what we want to do is we want to create a new drawing.

So, I'm going to click on the plus.

I'm going to get create new drawing,

and the first thing it's going to ask me for is some information about how to set up

the drawing.

We're going to use a template for the drawing that's gonna give us our format.

So, like the all the markings around the side and the title block.

And we're gonna use as we will with every

item

in the course,

we're gonna use ME EN 272

B size—that's what the B stands for.

In this case, we're working in millimeter units,

so we're gonna choose the mm format.

You can find the inch format in another place,

but right now, we're just gonna

do the MM format.

This happens to be version 6.

You should be taking whatever is the latest version.

And we're going to

use that. And so, now it's bringing in all of this important stuff

that is around the side including the revision block,

the title block, all of the stuff that goes around the side.

and this is a B size drawing. You should understand that

a B size drawing is 11 by 17—11 by 17.

OK.

And so,

it's a big drawing.

And

that's a standard size that I prefer for drawings.

So, you can see there's a lot of stuff not filled in here.

OK.

We don't know anything about the release date.

We don't know anything about

who has drawn it.

It's not been checked.

We don't know anything about the units.

There's a lot of missing stuff. We're gonna show you how to get that all worked out

right now.

The first thing that we need to do is we need

to tell it which part we're gonna be creating a drawing

for.

And the part we're gonna create a drawing for is in the SS button

area,

and it is the SS button.

So, I'm going to click on that, and once I've done that,

it is now bringing into me the very first view which it's bringing in the front view.

When I made my model,

what we're seeing right here is the front view.

So, the moment you start thinking about the drawing is

the moment you start making the actual solid CAD model.

That's when you're making your first sketches, and you're saying where

should I put the first sketch. Should be on the front,

the top,

the right,

blah blah blah?

This is how you determine that. You determine that by

knowing that the drawing wants to put the

front face

right in this orientation.

Now, you just click anywhere, and it will pop it in

there, and then it automatically wants to give you an orthographic projection,

which you can just click where you want it to go.

And

then, if you want another orthographic projection,

you should click back on the front face

and come on over here, and now we have our right view.

So, these are the standard orthographic projections—front,

top,

and right.

So, we definitely want those in there.

Of course,

when we look over here,

we see there's yet another one, which is the bottom.

We'll get to that in a minute.

We're going to put in our ISO views right now. And why do we want to put on our ISO views?

Because those are the standard

views.

OK.

So, I'm going to insert a view right up here,

and the view that I'm going to insert is not my front view.

We already did that one.

OK.

We're going to put in our isometric view.

And then I'm gonna put my asymmetric view right up in this corner,

which is where

our

standard is for putting our isometric views

in our course.

And this right here represents the standard set of

views that should be in a drawing.

Now,

the main goal of any drawing is that it be

clear. And so, that means we sometimes have to add views,

sometimes have to remove views,

but generally speaking, this is the general set of views.

Now, every one of these views can be moved,

and what you should know is that when they're orthographic projections,

the

two,

the

views will all move relative to each other because

they are projections of each other.

So, they need to be in the right spot.

And later, we'll move these all around as we will need

to do that.

Now that we know what part we're making a model of,

I am going

to

show you how you get

this document to kind of fill out in a nice way.

All right.

So, item number one

is we have to understand that everything in the title block right here

comes from

metadata. It comes from another place.

And the place that it comes from is two places:

the things that are related to the drawing itself such as who drew it,

okay,

the

date it was drawn,

the date it was released,

the revision of the drawing.

These are all embedded in the properties of the drawing.

So, I'm gonna come over here and look at the drawing itself.

But the first thing I'm gonna actually do is rename this

drawing because we don't want it to be called drawing 1.

We want it to be called

SS

button.

Here,

we'll go SS button.

All right.

Now,

if I right click on this,

I will get into the properties.

When we get into the properties,

we're gonna see some important stuff.

OK.

We're gonna see the name of the file,

which I just called it SS button.

We're

gonna now see the title.

OK.

This is

the

Start

Select

Membrane

Start/Select Membrane is what this is.

OK.

Who is the person who created the drawing?

Take a look at the format here,

first initial,

second initial,

last name,

C.

A.

Mattson.

And

it needs to all be caps,

but this is programmed.

So, it's all gonna come up in caps no matter what you put in here.

What is our drawing date?

Let's make the drawing date today.

August 9th in this case.

Who's checked the drawing?

Well,

it's really important to not put a fake person in here.

You need to actually be honest, and you need to have good ethics.

This is gonna remain as not checked until someone else has checked it.

What is the check date?

There's no check date because no one has reviewed it yet.

OK.

OK.

Oftentimes, before we actually release

a

a

design

or a set of drawings,

and we're in working,

and we're just gonna go back and forth with team members and stuff like this.

I like to go with alpha,

shoot me a numeric

revision number.

So, we'll call this drawing revision 1.

Once we feel like we have a final version,

we will switch that to A.

So that might mean we go from like version 13,

which has been like pre-release development,

to actual release,

then we'll call it A.

OK.

And

so, we're gonna be Revision 1 for this.

OK.

This is

the initial release of the drawing,

some comments.

Where the comments gonna go?

The comments are gonna go down here.

So,

we already know we're gonna have a color specification—

color

specification.

OK.

And we're gonna go see in a few minutes what those are,

but there's gonna be an R number,

a G number.

OK.

I'm just trying to get this formatted right,

or at least consistently,

and a B number.

OK.

there is a part number,

but this part number

is

not gonna populate from here.

This would be

better described as a drawing number.

But frankly,

this

is an

Onshape property,

so it's not changeable by me,

but the part number for the actual part is gonna come

from the metadata for the CAD model of the part,

not from the metadata of the drawing.

OK.

So, it's good to keep track of just sort of what's going on there.

OK.

Last

change.

Last change by me.

We're gonna apply that.

And when we do apply that, we see some stuff that has appeared down here.

OK.

We at least see that we have a proper name—Start/Select Membrane.

OK.

We see that I've created this, and this is the date that it was created.

We also see that it's not been checked yet, and there's no date for that.

We do see that it's silicone rubber,

which is really great.

This is

coming from the metadata for the part.

So that's great,

which also means the weight

or the mass is coming in correctly.

We

have not specified any finish,

and this is our color specification that we've left undone.

And then, this units thing is all super messed up.

It says inch.

OK.

So, I'm not really sure what to do with that, or

you might be thinking you're not sure what to do with that,

and I'm gonna show you right now how to handle that.

OK.

So, look,

we also have,

we're in revision 1 for this.

So, it's a pre-release revision, and we got

revision 1 right up here called initial release.

We actually probably could have switched that to

pre-release.

OK.

In fact,

I'll just do that right now to show you that

it's just really easy to do these kinds of things.

OK.

Where did that go?

Where did that go?

It's right in here.

Pre-release.

And again,

this is going to become automatically caps over here,

which is what we

want on our engineering drawings.

They need to all be

in caps.

OK.

We're almost done with sort of the setup of this.

OK.

OK

But,

we have a little bit of information that's not working out right yet.

And what we need to do for this is go into the metadata for the actual part,

not the metadata for the drawing.

So, we're gonna go back over to

the part studios, and we're gonna go into the SS button,

And as we go into the SS button,

we are going to right click on SS button and go to properties.

And we have to be sure that we're actually in the properties section or, excuse me,

not in the part studio section,

but the part.

We want to be in the part.

So, we're gonna click into the part here.

And we can see that we have not written our

part number here, which is why it hasn't shown up

anywhere on there yet.

So,

we're gonna need to go get that,

and I'm just gonna put some numbers there for a second so we can see that populate.

OK.

This is for the NES project.

OK.

Our material is silicone rubber, and that's really great.

And here's our problem unit of measure—inch.

That's what we saw on our title block,

right?

This is where we need to go in here and select millimeter

as our unit of measure, and make sure you don't select milliliter.

We're gonna get millimeter.

OK.

Apply that.

And

then we're gonna close that.

What we need to do is

we need to spend a little bit of time

making sure we understand what this part number is.

And so, we're gonna go back over into

this tab

and into our assembly studio, and I told you that I had put the NES controller

drawing in there for reference.

And when we go in there, we're gonna see our part number

because it's going to be on the bill of materials.

The bill of materials is the list of all of the items that are part of an assembly.

And that is usually found on the second sheet of an assembly drawing.

So, which part are we looking for?

We're looking for part 4.1.

OK.

4.1.

4.1 is the Start/Select Membrane.

OK.

And that's part number

4002-NES.

OK.

So,

now, we can go back into our

part studio

and right click on our SS button

and change the properties for that

and make sure we're not looking at the part studio but the actual part.

And we can change our part number to

4002-NES,

and we can apply this.

We can close this.

Now, we can get back over into our

drawing area,

and we can look back at the SS button.

And interestingly,

it didn't update.

But the reason why it didn't update is because with Onshape,

you'll see this yellow button up here.

This means that the model is changed, and the drawing needs to be refreshed.

So, I'm going to click on that.

And when I do, our part number shows up. And what else shows up?

Millimeter.

We haven't put our color specification in there yet.

So, if we look at this and we see how complete are we

in the title block,

it's not been checked yet,

but it's honest right now.

That needs to be done.

But can't be done

at the moment since I don't have someone here checking it.

OK.

OK.

Millimeter is correct;

silicone rubber is correct;

not specified finish probably needs to be fixed;

color needs to be fixed.

Our part number is correct;

revision is correct.

The mass is right.

Scale is right.

B size drawing is right,

and the title

is right here.

So, we have almost set up our drawing completely

the way that it needs to be

set up.

OK.

OK.

I'm gonna go fix these things right here.

OK.

The color specification,

and then I want to show you one more thing that I think is really important.

OK.

First of all,

we can see right here

that we need to have texture MT 11,010.

This is a mold tech standard.

It means that there's a texture that appears on the molded part.

Almost all plastic parts have textured surfaces,

and MT,

pardon me,

MT 11,010 is a really

common one.

OK.

So, that's what this one is gonna be.

And then, our color specification is gonna be

R89,

G96,

and B102.

OK.

And then, we have the MT 11,010

is our texture.

So, once we get that fixed up,

then we have finished completely

everything that's needed for sort of setting up

the drawing

and getting the title block right and all that kind of stuff.

Now, this is in the metadata of the drawing.

OK.

So, we're gonna come in here into our properties,

and we are going to

check and change these things.

Pre-release finish.

Here we go.

OK

Textured

MT

11,010.

All right.

And then, our R color is R89.

OK.

G.

96.

and B 102.

102.

OK.

I make these all look right.

So, I need

to have a space right there.

All right.

And then, we are done with that part.

So, we're gonna apply that

and close that.

It's helpful to understand

what metadata is being pulled from where.

And I've just described that.

So, if you need to go back and look at it again,

I recommend that you do that.

OK.

Let's assume for a minute,

which you're not going to have to do for the exercise,

but let's assume for a minute you want to add a second page.

This is important because this will also show you

how you need to set up your second page.

First of all,

all the pages are right over here on this tab

set.

OK.

And

I'm gonna create a new sheet,

and I'm gonna insert a sheet.

Now one of the things that you need to know

about our standard for drawings is that the first sheet,

this one,

has the revision history on it,

and our second sheet

should not have the revision history on it,

but it does have the revision history on it.

So, I need to show you now how you make

a fix to that.

OK.

You can click off here onto the side

and look for sheet properties.

And when you look in sheet properties,

it's asking for what your format is that you want to have.

So, you can have a different format for sheet 1 and a different format for sheet 2.

And right here is where I get to select

the sheet format that I want.

Now, I'm going to have to find

this

other one, and

it will be provided to you. So, you just have to make sure you understand where it is.

In this case, it's going to be in BYU Design under Design Formats,

and then I'm going to click on the Drawing Formats, and I have two format options here.

One is the 272 B MM format,

and one is the 272 B MM continuation,

which means sheet continuation.

So, we need to click on this one.

And then that brings that in, and what has happened,

the revision block has gone away,

and everything else remains the same.

So,

once I add in that someone has checked this,

it will apply to both sheet 1 and sheet 2.

OK.

Now, I'm gonna delete sheet 2 because we don't actually need it.

So, I was just showing you how you could add that in there.

Now, the portion of the video

that remains because we have the title block completely settled,

what we need to work on is getting a drawing,

making a drawing

that looks like

this drawing here.

OK.

I want to take care of my scale first because

I'm seeing this scale is 2.1, and I believe our scale over here was 3.1.

Yeah,

yeah,

3,

excuse me,

3 to 1.

And the way that we do that is,

well,

number one,

we can right click over here, and I think we can look at sheet properties.

And look,

yeah,

we have scale.

Scale

is listed right there.

Let's switch it to 2 colon 1.

And this switches everything to the smaller size.

That's good because we have a lot of things we want to put on this sheet.

So,

that settled that problem.

OK.

Let's

get the other views in place that we want to have at this point,

and let's get them in approximately the right spot.

We know we want to have a bottom view.

That means we need to add a projection view.

How are we going to add a projection?

Well,

this is to insert a view,

but this is to insert a projected view

or to create a projected view.

So,

projected view.

If

I do that,

then I got my bottom view.

And I also want to get a projected view of this.

How's that gonna happen?

OK.

There's that one,

and that doesn't really look like the one that existed in the other drawing.

Or does it?

OK.

OK.

Let's go back and look.

No,

it does not look right.

So,

there's a couple of strange things that we can do here.

We

have to keep doing some projections

to see where we get.

OK.

That's not it.

That's not it.

That's the one we started off with.

And at some point, it's going to go around in a circle if we go just in this direction.

So, I'm gonna take this one and go like this.

OK.

That's also not looking right.

OK.

And that's not looking right.

This seems like a futile way to do this.

I guess,

now we've got to run back to the getting close to the other one.

How do we,

how are we gonna do that?

Well,

I think there's another way we can do it as well,

and that is

let me

escape out of that and grab all these

views and delete them because they're in the way.

I'm

gonna come over here, and I'm gonna look at what this looks like.

OK.

And I'm gonna go into my actual part studio,

and in my part studio,

back into the SS button.

And I'm going to go over here to these views,

and I'm going to look at my isometric view for a second.

OK.

This is my isometric view that it appears this way is the

isometric view and in the drawing as the same exact view,

but I wanna see another one of these.

So,

if I click on these corners,

I'm gonna see other ISO views.

OK.

Is that the one that we want?

OK

Let's go...

Let's go see.

OK.

I'll go back into here,

then I'm gonna go into my drawings,

then I'm gonna go into here.

OK.

Now,

we want this rounded part in the back,

this rounded part in the back,

and then we want to see both of the buttons

just a little bit.

OK.

So, coming back over here into the part

studio

into my SS button.

I wanna see if there's

any,

so

the thing in the back.

We want to see one that's close to this.

OK.

I think that's

actually

close to being it.

So, let's go check one more time

into our drawings,

into the reference that we're going for.

Yeah,

I'm gonna

go for that as being good enough slash correct.

So,

we're

gonna go into our

part studio.

And we're going to put a name on this view

that we're looking at right now.

Named view.

Iso bottom.

OK.

And I'm gonna

save that.

OK.

Save that view is what I meant.

I'm gonna go back over to my drawings

and into this part of the drawing

and into our actual one that we're creating,

and I want to double click on this.

And

Iso bottom.

OK.

My view that I saved is now there.

OK.

So, that's close.

It's actually not exactly right because the other

button was sticking up a little bit.

So, we could

adjust that.

But I'm gonna go

with this one right now.

OK.

As a good for this exercise.

OK.

So, we have a couple of other things going on here

that we want to take care of.

We have our basic views.

Let's get the notes in here.

Hidden lines removed for clarity.

Let's add that note in.

The way that you add a note into this

is you come up here and you find the A,

not the A that's in the box,

but the A that's like this.

That's our note,

or we could have just clicked N according to that.

And what we need to know is that this is coming out in lower case,

and we need to know that our engineering

drawing standard

requires everything to be in uppercase.

So, I've just put the cap blocks on.

And

I'm gonna hit return and

do a one for my first note.

And I'm gonna say "Hidden

lines removed for clarity."

What does this mean?

First of all,

what I need to do now is click in another place

and then hit escape.

And if you do that,

you will not lose the note that you just created.

OK.

I'm gonna extend this out like this, so it can become a longer note if it needs to.

And then, I'm gonna come just tuck this right on top of the title

block area.

OK.

What does this mean?

Our isometric views should have the, excuse me,

our orthographic projections should have

the hidden lines on them.

And currently, they don't

because they come in as a default without the lines on them,

but our standard is that they need to have the lines.

So, if I go over here to show and hide.

OK.

What do I wanna look at?

Show hidden lines.

OK.

There's my hidden lines on that one.

OK.

Let's show hide on this one;

show hidden lines on this one.

OK.

And show hidden lines on this one.

Show hidden lines.

I actually just wanna see what they look like,

and I wanna look at show hidden lines on this one.

Show hidden lines.

OK.

This

would

not have been that bad actually for

these hidden lines to be present.

I don't think it makes it actually that complicated.

So, for clarity's sake,

I'm actually gonna leave them on.

OK.

I'm gonna leave them on because I actually think that's good.

Now, if I go over here,

I just want to take a look at this for a

second.

That's not what I want.

Let's get out of our drawing properties.

OK.

I'm gonna look at the sheet properties for a second and see if there was

any way

to have changed all those at the same time,

and it doesn't appear that there was.

So,

we've

added our hidden lines to this.

And

so,

we're

gonna take off this note.

And I'm just gonna write none for now,

as there's no notes.

OK.

Now, we have not put

hidden lines on isometric views because they're never allowed.

They're never allowed because it clutters up the drawing way too much.

OK.

And

you know,

now I'm rethinking this.

I

wanna actually just ask you to

reproduce this drawing right here.

So, do it without hidden lines.

I'm vacillating a little bit here.

So, I'm gonna put this note back in

that just says "Hidden

lines

removed for clarity."

And actually,

I'm gonna just go in and

take all those off.

I think I can do this at once,

maybe if I right click on here

and

that is not true.

I cannot do that.

So, I need to do it on each one separately.

And I want to hide hidden lines,

and then right click on this and hide hidden lines,

and right click on this and hide hidden lines,

and we are almost done.

So,

it

took 20 seconds.

I wish it would have taken 5 seconds.

OK.

Now,

we're gonna start adding.

We're

gonna actually get our other view in here,

and that other view is we need to get our detailed view,

and then we also need to get a cross-section view.

Let's start with cross-section because this is such a fundamental part

in creating drawings that we want to make a cross-section.

OK.

So, we want to slice this thing right up here.

Let's zoom in on this.

OK.

And the way we're gonna do that is we're gonna get the cross-section marker—

Section View.

OK.

We're gonna tell it whether it's gonna be vertical or horizontal

or whether it's gonna be at some angle.

We want this to be horizontal.

There we go.

OK.

And

we want it to be lined up nicely with

the center of this.

So, I'm gonna pick that one.

And now, you can see it's starting

to

put my cross-section somewhere.

I'm just going to click up here.

This is obviously not where it's going to go,

but I'm going to put it up there for a minute

and show you a couple of things that we can do.

First of all,

I

can come in here and double click on this,

excuse me,

double click on this.

And I can decide to show just the cut geometry.

OK.

And if I do that,

just pay attention to these lines right in here.

OK.

We

only get what we see through the slice.

OK.

It's also ridiculous to have this up here in this area.

So, I'm gonna show you right now how you can move it.

First of all,

it's stuck

to the orientation of this part.

So,

you know,

when I move it,

they move together,

but I can suppress that relationship,

which is quite common for

cross-sections.

I can suppress the alignment with the parent,

and then I can just move this wherever I want to move it.

OK.

Let's see if the reference drawing has a slice or does not have a slice.

OK.

It does not have a slice.

So, we want to go

not just look at the cut geometry,

we want to look at the actual

full cut.

So, I'm gonna come into here.

And actually, I'm gonna come back to this marker,

and I'm not going to look at just that.

OK.

And so, that's gonna put that information back.

Now, one of the things we notice

is,

well,

first of all,

I can switch these directions.

It's not gonna change the cross-section

at all.

Well,

it actually will change it just a little bit.

OK.

But that's how we have it in the reference drawing.

It's going up,

so I'm gonna make it go up.

We can also see over here that the cross-section has a

finer pattern.

And ours has a not fine pattern, and it becomes less obvious near these other lines.

So, let's figure out how we can change that.

If we double click on this,

actually I don't want to double click on that.

What I want to do is I want

to...

How do I want to do that?

I am going to,

I think,

right click

on this and edit the hatch pattern,

edit the hatch

section.

OK.

And the hatch that I want to change is this hatch

right here,

and the scale that I want is something different,

something small,

smaller,

is this as small as it gets.

That's kind of odd.

Let's try that one more time.

I want to edit this,

and I want to edit the hatch section.

And I'm gonna choose the section that I want,

which is that one,

and

hm,

I can change

the,

okay

that scale.

I can make it bigger,

but I can't seem to make it smaller.

That's not cool.

Can I...

Can

I

type it in?

All right.

Well,

we're gonna have to go with this one like this for now

since I don't know exactly how to do that.

OK.

Let's actually find out if we were to do this.

OK.

If we went...

If we...

So, I'm not gonna worry about that.

We're just gonna take the hatch like that for now.

All right.

Then, we're also gonna have a detail view.

And the way we do a detail view is we click the

detail view button,

which is this one.

OK.

And we can zoom in to about where we want it to go,

and I want that section view to be right in here.

Now,

remember,

if I do my section view like

this,

I'm gonna show you what's gonna happen with this.

OK.

I do my section view like this

and then I pop this over here,

I have this geometry up here that's like not super useful.

right?

And so,

if I want to change that,

I've got to grab right where near the B is.

OK.

And I'm gonna shrink it

to just below that

so that it's just looking at that part.

OK.

Then, what I can do if I want to,

which I do.

So I'm gonna change the scale of that.

This is changed to 8 to 1.

OK.

Button

8 to 1.

I am

gonna

double click on this,

oops,

not that.

I double click on this part,

and I can change the scale right here to 8 to 1.

There's probably a drop down for it.

Yes,

there is.

And

I'm gonna

take it that way.

So, at this point,

we have all the views that we want.

We have set up our drawings so that

it's

got

all the information in the title block correctly.

And now, at this point, we just have to add the dimensions.

So, what I would recommend doing is trying to add the dimensions

yourself

based on what you think needs to be dimensioned.

And the bottom line is everything needs to be dimensioned once and not twice.

So, to create a dimension,

we are actually just gonna hit D—the

way we did when we were in the sketching environment.

And we're going to

do exactly like we did when we're doing sketches

in the solid CAD modeling.

OK.

All right.

I'm

gonna pop in some dimensions here,

and these dimensions,

I'm just gonna keep going on them

for a few minutes.

OK.

It's

really important when you're doing this kind of thing that

you don't like actually accidentally get one of these small things.

You wanna

get the actual thing that you're trying to dimension to,

so not the edge of a fillet

or anything like that.

OK.

I'm just gonna place this stuff out there, and as I place this stuff out there,

there's gonna,

I'm gonna have to make some changes

to the stuff.

But,

you know,

it's okay.

Up here,

it's

gonna be helpful if I add in some center marks.

Here, we automatically have a center mark that it's appeared.

That's kind of nice.

OK.

And

when I dimension stuff,

we can know that something is concentric because this points right to the center.

So, when I do this,

we can know that these two things are concentric with each other.

OK.

We also have

this dimension that we have to think about.

And we have this dimension that we have to think about.

OK.

And there's a lot of dimensions here that need a little bit of help,

but I would like to put some center marks on these.

The way that you put a center mark on is you get out of the

dimension in command because I got a little plus on there by hitting escape,

and I'm gonna come up here to my center mark,

and then I'm going to click on the things I want a center up for.

I want a center for that.

I want a center for that.

I want a center for that.

I want a center for this.

OK.

OK.

What else do I want to send her for?

Yeah,

I wanna center for some of these things that are down here.

So, like this one.

And this one

and this one

and this one.

And I think that's about all I'm gonna need a

center mark for, but we can always add more center marks

later.

OK.

I'm gonna keep dimensioning this.

So,

dimension.

I've got to

dimension this part,

and I also need to dimension this part,

and I need to make a decision about whether I'm gonna dimension this inner part

or whether I'm just gonna say there's a thickness.

OK.

And then,

I've got to do

one of these up here.

We have to remember that this is the top of a radius.

What I mean by that is,

that's the top of this radius,

like this point.

We don't want that.

In this,

in right over here being

dimensioned,

we want

not that one.

OK.

We want

that one.

OK.

I'm gonna pop that down there.

OK.

Now,

all these dimensions over here are identical to these dimensions.

So, we're gonna have to make an adjustment on it and put 2X or 4X or whatever

on it to know that

that's gonna be there so we don't have to have so many

dimensions.

Let's take a look at our reference drawing for a second.

OK.

Up here, we wanna

get

this edge to, excuse me, this center to this center

at 22, and then the distance between these at 2,

and we need to add this one be 2X.

So, let's go learn how to do that right now.

All right.

We're gonna do D for dimension. We're already in it because there's a plus.

I'm gonna get from this center mark

to this center mark.

OK.

And there's my 22.

And then, I'm going to get from this center mark to this center mark,

and there's my 6.

OK.

Now,

this 6 needs to have a 2X in front of it.

And the way that we're going to do that is we're going to double click on it.

And when we double click on it,

we can put whatever we want here in front of it,

2X,

for example.

But I need to put a space.

OK.

And then, I'm going to click out here to be done with it,

and there's my 2X 6.

OK.

Let's go back and look at our reference drawing.

OK.

Then, we're gonna have

this thing here that says typical.

OK.

And this thing here that says typical,

and this thing here that says 2,

and this thing here that says 2.

Let's go take care of

this one and this one,

and then this one and this one.

OK.

All right.

So,

SS Button.

OK.

This is the one of them over here

that

it's gonna get too crowded in this area.

So I'm gonna delete this.

Or actually, I could delete it and put a new one in,

or I'll show you what else you can do,

which is

I can grab the point

and go move it to something else

like this.

OK.

Sometimes that's useful.

Not always,

but sometimes.

OK.

I'm gonna hit D to make another dimension and get this one.

OK.

Gonna move these around just a little bit.

OK.

Like this.

And this one needs to be 2X.

So, I'm gonna double click on it.

OK.

So, I'm gonna put a 2X space.

OK.

And then, this one I'm gonna do the same thing—

2X space.

OK.

That's looking really good.

OK.

This one also has 2 because there's this one and this one,

and then there's this one and this one.

Those are two different numbers.

So, let's go

fix that.

2X,

great.

Double click on this one.

OK.

Get out of there.

Double click on this one,

2X.

OK.

That's looking good.

OK.

This one only has one;

this one only has one.

So, those ones

are

like definitively the way they are now.

OK.

This

one right here,

these said typical.

What does typical mean?

Typical means that

this dimension appears in multiple places

that aren't necessarily in the same orientation or like 100% obvious.

And

so,

it's

good to do that for like things like

thicknesses of parts and stuff like that,

but I'm gonna do this as a way of demonstrating how you do it.

So, after the dimension space TYP.

OK.

Now,

we're gonna double click on this,

pull this thing over here,

after the dimension space TYP.

OK.

And that is

that.

I think we have most of those dimensions on there.

OK.

And we wanna just sort of straighten them out and have them look nice.

OK.

Whenever you have a radius,

it's important that your radius isn't pointing too much to a flatline

like this.

We're gonna try to get it up there into the curve.

OK.

So, that's

a pretty good spot right there.

Pull this one in just a little bit.

OK.

And that's looking just about right on how we do the dimensions.

Now,

we can go through the process of

adding in all the remaining dimensions.

But I'm gonna let you do that as a way of exercising.

I don't think you need much of a demonstration anymore.

Let's go back and look at the SS button and see if there's any strange things

that we need to pay attention to.

OK.

We need to figure out how to get this line in here,

this center line.

See the dash line,

this is like

three typical to the center of this.

I'm gonna show you how to do that.

And then,

we have covered just about everything.

So, even though we haven't produced the drawing completely,

I'm gonna leave that to you.

But we're gonna go to the SS button right here, and I'm gonna show you how to get

that center line in there.

So, we have a center mark, which we already talked about

a few minutes ago where we click the center mark button,

but there's also a thing here called center line

or edge-to-edge center line.

OK.

So, if I click on this,

what I can do is just pick one edge and another edge,

and I get a center line,

and that's really great.

I can escape out of this, and because I actually

want that center line to extend all the way down,

I just grab it and try to have it go below the part as much as it's going above the part.

And now, I can create a dimension

from say this

to this

and we get a number.

Now,

interestingly,

it's

your

dimension will come out from the direction you've made this go.

So, sometimes you have to just move around a little bit in order to make that

happen.

So, this one was a typical because it actually shows up in various places,

oops,

not type, TYP.

OK.

That's from here to here,

and then from here to here,

and then from

here to a center line here,

and from here to a center line

here.

So,

it also would have been appropriate to say 4X,

but in this case,

we're just gonna go with the TYP.

OK.

What did we do in this video?

We went all the way from

talking about the good CAD process of

understanding the job that needs to be done,

getting the sketch and the strategy together,

then doing the CAD modeling,

then analyzing to see if we've done a good job,

to adding this fifth part to it,

which is presenting the work.

OK.

As we present the work,

we can do this in

renders,

screenshots,

animations,

also engineering drawings.

Now, we have learned how to start an

engineering drawing for a part that you have created.

A lot of that was getting the title block set up

and getting the metadata connected to the properties of

the drawing and the properties of the part.

Then, we simply had to get go in and put in our

views,

the standard orthographic projection views,

also the ISO views,

and then get in a few auxiliary views like the detail view,

the section view,

and then we had to go start doing

the

dimensioning.

And then, what you would need to do in this case to finish this up

is you would add in all your dimensions,

then you would make sure everything looks nice and clean.

So, for example,

we're a little too close up to this edge up at the top.

So, I'd be taking this down

like this,

getting this arranged just a slightly nicer, so there's

a little bit more breathing room between the parts.

And now, I have in my drawing

my

ISO views,

I have my orthographic projections.

Of course,

we've gotten right over to this edge,

which we don't wanna be there.

So, let's

pull this over here just a little bit

more

and give the right view just a little bit more space in there.

And we have our section view off to the

edge. We would just clean up our drawing and make it look good

and professional,

and then this is the presentation

of the geometry we created

in the CAD system in our solid CAD modeling. So, that's like our fifth part

in the good CAD modeling process is learning how to present. Here,

you learned

the basics

of engineering drawings. And just as

the case with everything,

it's gonna feel pretty foreign here at the beginning, but after

a while, it'll become quite natural to create engineering drawings.